# <!-- document.writeln("<font color=" + '#000000' + ">Viewing X-Sectional Results</font>") //-->

## <!-- document.writeln("<font color=" + color4[0] + ">Introduction</font>"); //-->

This tutorial was created using ANSYS 7.0 The purpose of this tutorial is to outline the steps required to view cross sectional results (Deformation, Stress, etc.) of the following example.

## ANSYS Command Listing

```FINISH
/CLEAR

/Title, Cross-Sectional Results of a Simple Cantilever Beam
/PREP7

! All dims in mm
Width = 60
Height = 40
Length = 400

BLC4,0,0,Width,Height,Length	! Creates a rectangle

/ANGLE, 1 ,60.000000,YS,1 	! Rotates the display
/REPLOT,FAST			! Fast redisplay

ET,1,SOLID45  			! Element type

MP,EX,1,200000 			! Young's Modulus
MP,PRXY,1,0.3			! Poisson's ratio

esize,20			! Element size
vmesh,all			! Mesh the volume

FINISH
/SOLU   			! Enter solution mode

ANTYPE,0			! Static analysis
ASEL,S,LOC,Z,0			! Area select at z=0
DA,All,ALL,0			! Constrain the area
ASEL,ALL			! Reselect all areas

KSEL,S,LOC,Z,Length		! Select certain keypoint
KSEL,R,LOC,Y,Height
KSEL,R,LOC,X,Width
FK,All,FY,-2500			! Force on keypoint
KSEL,ALL			! Reselect all keypoints

SOLVE				! Solve
FINISH

/POST1 				! Enter post processor

PLNSOL,U,SUM,0,1		! Plot deflection
WPOFFS,Width/2,0,0      	! Offset the working plane for cross-section view
WPROTA,0,0,90			! Rotate working plane
/CPLANE,1               	! Cutting plane defined to use the WP
/TYPE,1,8               	! QSLICE display

WPCSYS,-1,0			! Deflines working plane location

WPOFFS,0,0,1/16*Length    	! Offset the working plane
/CPLANE,1                 	! Cutting plane defined to use the WP
/TYPE,1,5                 	! Use the capped hidden display
PLNSOL,S,EQV,0,1		! Plot equivalent stress

!Animation
ANCUT,43,0.1,5,0.05,0,0.1,7,14,2 ! Animate the slices
```