This tutorial was created using ANSYS 7.0 The purpose of this tutorial is to outline the steps required to view cross sectional results (Deformation, Stress, etc.) of the following example.
FINISH /CLEAR /Title, Cross-Sectional Results of a Simple Cantilever Beam /PREP7 ! All dims in mm Width = 60 Height = 40 Length = 400 BLC4,0,0,Width,Height,Length ! Creates a rectangle /ANGLE, 1 ,60.000000,YS,1 ! Rotates the display /REPLOT,FAST ! Fast redisplay ET,1,SOLID45 ! Element type MP,EX,1,200000 ! Young's Modulus MP,PRXY,1,0.3 ! Poisson's ratio esize,20 ! Element size vmesh,all ! Mesh the volume FINISH /SOLU ! Enter solution mode ANTYPE,0 ! Static analysis ASEL,S,LOC,Z,0 ! Area select at z=0 DA,All,ALL,0 ! Constrain the area ASEL,ALL ! Reselect all areas KSEL,S,LOC,Z,Length ! Select certain keypoint KSEL,R,LOC,Y,Height KSEL,R,LOC,X,Width FK,All,FY,-2500 ! Force on keypoint KSEL,ALL ! Reselect all keypoints SOLVE ! Solve FINISH /POST1 ! Enter post processor PLNSOL,U,SUM,0,1 ! Plot deflection WPOFFS,Width/2,0,0 ! Offset the working plane for cross-section view WPROTA,0,0,90 ! Rotate working plane /CPLANE,1 ! Cutting plane defined to use the WP /TYPE,1,8 ! QSLICE display WPCSYS,-1,0 ! Deflines working plane location WPOFFS,0,0,1/16*Length ! Offset the working plane /CPLANE,1 ! Cutting plane defined to use the WP /TYPE,1,5 ! Use the capped hidden display PLNSOL,S,EQV,0,1 ! Plot equivalent stress !Animation ANCUT,43,0.1,5,0.05,0,0.1,7,14,2 ! Animate the slices